Skip to content

Reference guide · Machinist speeds, tap drills and shop geometry

Tap drill size for 50, 65 and 75 percent thread

By the Mirage Interactive team · Last checked

A tap drill size is a compromise. A smaller drill leaves more material for the tap to cut, which makes a deeper thread, a higher thread percentage and a stronger hold, but it also loads the tap harder. A larger drill is easier on the tap and gives a shallower thread.

The usual chart value is the drill that leaves about 75 percent of a full thread. This guide gives the drill diameter for four percentages and shows what percentage a given drill gives, so you can see the trade before you choose.

The short answer

Drill diameter = major diameter - 0.01299 x percent x pitch. For M8 x 1.25 at 75 percent the drill is 6.782 mm; at 100 percent it is 6.376 mm. For inch threads use pitch = 1 / threads per inch.

Thread percentage = (major diameter - drill) / (0.01299 x pitch). A 6.7 mm drill in M8 x 1.25 gives 80.1 percent on the nominal thread, and a 6.8 mm drill gives 73.9 percent.

Tables

The first two tables give the drill diameter that leaves 50, 65, 75 and 100 percent of a full thread: metric coarse threads in millimetres, UNC threads in inches. The third gives the percentage that whole 0.1 mm metric drills give on four common metric threads. Use your browser's print command to print this page: the tables print without the navigation.

The tap cuts the ring between the drill circle and the major circle. A smaller drill leaves a deeper ring, a higher thread percentage and more load on the tap.
Tap drill diameter in mm for 50, 65, 75 and 100 percent thread, metric coarse threads
ThreadPitch (mm)50% (mm)65% (mm)75% (mm)100% (mm)
M3 x 0.50.52.6752.5782.5132.351
M4 x 0.70.73.5453.4093.3183.091
M5 x 0.80.84.4804.3254.2213.961
M6 x 115.3515.1565.0264.701
M8 x 1.251.257.1886.9456.7826.376
M10 x 1.51.59.0268.7338.5398.052
M12 x 1.751.7510.86310.52210.2959.727
M14 x 2212.70112.31112.05211.402
M16 x 2214.70114.31114.05213.402
M20 x 2.52.518.37617.88917.56416.753

Source: computed by the site build from the formulas below.

Tap drill diameter in inches for 50, 65, 75 and 100 percent thread, UNC threads
ThreadThreads per inch50% (in)65% (in)75% (in)100% (in)
#8-32 UNC320.14370.13760.13360.1234
#10-24 UNC240.16290.15480.14940.1359
1/4-20 UNC200.21750.20780.20130.1851
5/16-18 UNC180.27640.26560.25840.2403
3/8-16 UNC160.33440.32220.31410.2938
7/16-14 UNC140.39110.37720.36790.3447
1/2-13 UNC130.45000.43510.42510.4001
5/8-11 UNC110.56600.54820.53640.5069
3/4-10 UNC100.68510.66560.65260.6201

Source: computed by the site build from the formulas below.

Thread percentage given by whole 0.1 mm drills on four metric coarse threads (nominal thread)
ThreadDrill (mm)Thread (%)
M6 x 14.984.7
M6 x 15.077.0
M6 x 15.169.3
M6 x 15.261.6
M8 x 1.256.686.2
M8 x 1.256.780.1
M8 x 1.256.873.9
M8 x 1.256.967.7
M10 x 1.58.482.1
M10 x 1.58.577.0
M10 x 1.58.671.9
M10 x 1.58.766.7
M12 x 1.7510.183.6
M12 x 1.7510.279.2
M12 x 1.7510.374.8
M12 x 1.7510.470.4

Source: computed by the site build from the formulas below.

Formulas

Drill for a thread percentage
drill = major diameter - 0.01299 x percent x pitch
Pitch is the distance between threads, in the same unit as the diameter. For inch threads pitch is 1 divided by threads per inch. The constant 0.01299 is the published figure behind the common thread-percentage formula.
Thread percentage of a drill
percent = (major diameter - drill) / (0.01299 x pitch)
For inch threads this is the same as threads per inch x (major diameter - drill) / 0.01299. It is the percentage on the nominal thread. A drill cuts a hole slightly larger than its size, so a printed chart often shows a lower percentage for the same drill.
Thread depth
depth = (major diameter - drill) / 2
This is the radial depth the tap has to cut on each side of the hole.

Worked example

M8 x 1.25 at 75 percent, and the two nearest drills

  1. Pitch 1.25 mm, major diameter 8 mm. At 75 percent: 8 - 0.01299 x 75 x 1.25 = 6.782 mm. The drills at 6.7 mm and 6.8 mm straddle it.
  2. The 6.7 mm drill gives (8 - 6.7) / (0.01299 x 1.25) = 80.06 percent, and the 6.8 mm drill gives 73.90 percent.
  3. A formula drill of major diameter minus pitch, 8 - 1.25 = 6.75 mm, gives 76.98 percent. That is the value many charts round to 6.8 mm.
  4. For M6 x 1 at 75 percent the drill is 6 - 0.01299 x 75 x 1 = 5.02575 mm; a 5.0 mm drill gives 77.0 percent.
  5. Chart percentages differ: a drill maker's chart prints 74 percent for the 6.7 mm drill in M8 x 1.25, because it counts the slightly oversize hole the drill actually cuts. The calculation here is on the nominal thread.

Things to watch

  • Thread percentage is not strength by itself. Tap makers often advise a lower percentage in hard or tough materials so the tap does not break; follow the maker's chart for the tap and material you have.
  • Values above 100 percent describe a hole smaller than a full thread needs. Do not drill there: the tap would have more to cut than a full thread asks for.
  • These are starting values. Drill wander, drill wear and the material change the hole you really get, so try a scrap piece first.

Related guide: Tap drill chart and cutting speed (RPM) formula

More from this family: Milling feed rate calculator: feed, chip load and spindle speed · Bolt circle calculator: hole coordinates and chord spacing · Cutting speed calculator: spindle RPM from SFM or m/min · Three-wire thread measurement: best wire size and measurement over wires · Taper per foot calculator: taper, half angle and diameters · Sine bar calculator: gauge block stack height for an angle

Skip the arithmetic

Cutting Speed, Tap Drill, Sine

Cutting Speed, Tap Drill, Sine gives the tap drill for a thread from a drill maker's table with the thread percentage and the source shown, and takes number, letter and metric drills and your own tools. One-time purchase · No subscription · Price shown in your store. Works offline, no ads, no account.

Questions

What is the tap drill size for M8 x 1.25?

Charts differ: some print 6.8 mm, which gives 74 percent on the nominal thread, and some print 6.7 mm, which gives 80 percent and takes more torque to cut.

How do you work out the tap drill for a percentage of thread?

Subtract 0.01299 x the percentage x the pitch from the major diameter, all in the same unit.

Is 75 percent thread always right?

No. It is a common general value. A lower percentage eases tapping in hard material, and a higher one gives more thread engagement in soft material.